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B-Pillar

2021-11-5 20:15| 发布者: 叶秋| 查看: 361| 评论: 0

摘要: Step 1: Publishing the Styling Inputs and Creating the Mating PartLoad the part called BPILLAR1_STYLE.CATPart from the ''Companion''.1. You are going to publish all the input data: In the “Tools” ...
Step 1: Publishing the Styling Inputs and Creating the Mating Part
Load the part called BPILLAR1_STYLE.CATPart from the ''Companion''.

1. You are going to publish all the input data:
In the “Tools” menu, select “Publication”:

The Publication window appears:

Select all the elements to publish in the tree:

These elements are added in the publication list:

Click OK to confirm the publication of the styling input data.


2. You are going to create a new Product:

In the “File” menu, select “New”:

And select “Product” in the new window:

Confirm by clicking OK.

3. You are going to insert the part in the new product:

In the window menu, select “Till Horizontally”:

You can see the first opened part and the new product:

Double-click on the product in the tree to access the infrastructure workbench.

Drag and drop the part in the product:

The part is now inserted in the product. You are going to begin the Mating Part design.

4. You are going to create a new part in the product:

Click on the part icon to insert a new part 
Select the product in the tree.
Select NO in the new window to make the origin of the new part the same as the product origin:

Rename this part “Part Mating”:

Double-click on Part Mating to access the Generative Shape Design workbench:

Copy and Paste as Result with link the published elements from the Part Style Inputs to the Part Mating:

Click OK to confirm the Paste action. The Copied elements are added in the Part Mating as External references. You can now hide the Part Style Inputs part and work with the copied data:

5. You are going to create the first offset:

Click on the offset icon  

Select the surface Y0 in the external reference open body.

Key in 725 in the offset field and orientate the red arrow into the external side of Y0:

6. You are going to fillet this offset with the surface Sur Design Ext:

Click on the shape fillet icon  

Select the offset surface and the Sur Design Ext surface.

Key in a 200mm radius and select the Maximum Extremity option:

7. You are going to Intersect Front Outer Support with Sur Design Front:

Click on the intersect icon  .

Select Front Outer Support and Sur Design Front as elements to intersect.

Click OK to confirm the intersect operation.

Rename the result Front Outer Intersection.

8. You are going to offset Sur Y0 and Sur Design Ext:

Double-Click on the offset icon  .

Select Sur Y0 and key in 700mm as offset:

Click OK and select Sur Design Ext and key in 20mm as offset value (toward the inside):

Click OK to confirm the offset creation. Click Cancel to close the offset dialog box.


9. You are going to fillet the two previous offset surfaces:

Click on the shape fillet icon  .

Select the two previous offset.

Key in 200mm as radius and select the extremity Maximum:

Click OK to confirm the fillet creation. Rename it Rear Outer Support.

10. You are going to intersect Rear Outer Support with Sur Design Rear:

Click on the intersect icon  .

Select rear Outer Support and Sur Design Rear:

Click OK to confirm the intersection creation and rename it Rear Outer Intersection.

11. You are going to publish the four created elements:

In the tool menu, select Publication:

Select Front Outer Support, Front Outer Intersection, Rear Outer Support and Rear Outer Intersection as elements to publish:

Click OK to confirm the publication of these elements.

Step 2: Creating the Outer Part

Load the product called Product_B-PILLAR2.CATProduct from the ''Companion''.


1. You are going to create a new part in the product:

Click on the part icon to insert a new part 

Select the product in the tree.

Select NO in the new window to make the origin of the new part the same as the product origin:

Rename this part “Part Outer”:

Double-click on Part Outer to access the Generative Shape Design workbench:

Copy and Paste as Result with link the published elements from the Part Style Inputs and the part Mating to the Part Outer:

From the Part Style Input:

From the Part Mating:

To the Part Outer:

Click OK to confirm the Paste action. The Copied elements are added in the Part Outer as External references. You can now hide the Part Style Inputs and Part Mating parts and work with the copied data:

2. Rear flange creation:

Click on the parallel curve icon  

Select the surface Rear Outer Intersection as curve to offset and Rear Outer Support as support 

Key in 15mm and orientate the red arrow toward external:

Click OK to confirm the parallel curve creation.

Select the split icon  

Select Rear Outer Support as element to cut and Rear Outer Intersection and its parallel curve as cutting elements:

Click OK to confirm the split creation and rename the result Rear Flange.

3. You are going to create the Front Outer Flange the same way and using Front Outer Intersection and Front Outer Support:

4. You are going to create the Upper Side:

Offset Surf Y0 (800mm toward external):

Fillet this offset with the surface Window:

Intersect Sur Design Rear with the previous fillet:

Intersect Sur Design Front with the previous fillet:

Split the fillet with these two curves:

Rename the result Upper Side.

5. You are going to create the Rear and Front Sides:

Split Sur Design Rear with Rear Outer Intersection and the first intersection curve:

Rename this split feature Rear Side.

Split Sur Design Front with Front Outer Intersection and the second parallel curve:

Rename the result Front Side.

6. You are going to fillet the five previously created surfaces:

Create a shape fillet with Rear Side and Rear Outer Flange  :

Split the result with B-Pillar Low Plane and B-Pillar High Plane:

Rename the result Outer.

Step 3: Creating the Inner Part

Load the product called Product_B-PILLAR3.CATProduct from the ''Companion''.

1. You are going to create a new part in the product:

Click on the part icon to insert a new part 

Select the product in the tree.

Select NO in the new window to make the origin of the new part the same as the product origin:

Rename this part “Part Inner”:

Double-click on Part Inner to access the Generative Shape Design workbench:

Copy and Paste as Result with link the published elements from the Part Style Inputs and the part Mating to the Part Inner:

From the Part Style Input:

From the Part Mating:

To the Part Inner:

Click OK to confirm the Paste action. The Copied elements are added in the Part Inner as External references. You can now hide the Part Style Inputs and Part Mating parts and work with the copied data:

2. Rear flange creation:

Offset Rear Outer Support toward internal: 

Rename the result Rear Inner Support. 

Project Rear Outer Intersection into Rear Inner Support and rename the result Rear Inner Intersection.

Parallel Rear Inner Intersection on Rear Inner Support: 

Split Rear Inner Support with Rear Inner Intersection and its parallel curve:

Rename the result Rear Flange.

3. Front Flange creation:

Offset Front Outer Support toward internal: 

Rename the result Front Inner Support. 

Project Front Outer Intersection into Front Inner Support and rename the result Front Inner Intersection.

Parallel Front Inner Intersection on Front Inner Support.

Split Front Inner Support with Front Inner Intersection and its parallel curve.

Rename the result Front Flange.

4. You are going to create the guide curves and spine for the adaptative sweep:

Offset Surf Y0 (640mm toward external):

Fillet this offset with the surface Window:

Intersect Rear Inner Intersection and B-Pillar Low Plane. Rename this point Extremity: it will be the spine curve starting point.

Create a Spine curve using B-Pillar Low and High Planes, Extremity as starting point, and Front and Rear Inner Intersection as guide curves:





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